What four-axis machining can and cannot do

• 1
  Key takeaways
• 2
  How the rotary axis changes the cut
• 3
  What tolerance four-axis machining can hold
• 4
  Which parts belong on a four-axis machine
• 5
  Where the extra axis stops helping
• 6
  Holding accuracy from setup to inspection
• 7
  Four-axis, three-axis or five-axis: which fits

A three-axis mill moves the tool along X, Y and Z. The workpiece stays clamped in one orientation, so every face you need costs you a new setup. Four-axis machining adds a rotary table or indexer, usually mapped to the A-axis, that turns the part about an axis parallel to X. The spindle still points one way. The part does the moving.

That distinction matters. Because the tool axis never tilts, you cut with the side of the end mill while the work rotates under it. Contouring a cam profile, milling a flat on a shaft, or drilling a ring of holes at equal angles all happen in one program. On a three-axis machine each of those features needs its own clamp position.

Most four-axis work runs as either indexing or simultaneous motion. Indexing rotates the table to a fixed angle, locks it, then cuts. It is simple, rigid and easy to inspect. Simultaneous motion keeps the A-axis feeding while X, Y and Z move, which is how you generate a helical groove or a continuous wrap-around surface.

The rotary table is the accuracy bottleneck. A Ø400 mm table with 0.01 mm runout at the edge throws that error straight into your part. Check runout before the job, not after.

• 1
  IndexingTable locks at set angles. Best rigidity and easiest verification.
• 2
  SimultaneousA-axis feeds with X, Y, Z. Used for helical and wrapped profiles.
• 3
  Chuck or fixtureRound work in a 3-jaw chuck, odd shapes on a tombstone or angle plate.
• 4
  Tool axis stays fixedNo tilt, so undercuts and steep walls remain out of reach.

We hold ±0.005 mm (±0.0002 in) on four-axis work, the same as our three-axis and five-axis cells. The rotary axis does not automatically cost you accuracy, but it does add error sources that a fixed setup does not have. Angular position error, table runout and backlash all compound with distance from the centerline.

Think in terms of radius. A 0.005° angular error is nothing at 20 mm from center and about 0.02 mm at 200 mm. Long parts amplify every rotary imperfection. If your drawing calls for a tight feature-to-feature tolerance on a 500 mm shaft, the rotary table has to be in good condition and the fixture has to hold the part on center.

Surface finish follows the same logic. Feeding the A-axis while cutting leaves scallop marks whose spacing depends on feed rate and radius. For wraps we typically land between Ra 0.8 and 1.6 μm, and reach Ra 0.2–0.8 μm with a finishing pass or a polished insert. As-machined faces run Ra 1.6–3.2 μm.

Materials behave differently on a rotary setup. Aluminium 6061 and 7075 cut cleanly at high rotary feed. Stainless 316 and 17-4PH work-harden if the A-axis feed is too slow, so keep the chip load up. Titanium TC4 and Inconel need lower surface speed and more coolant, and the rotary table sees more torque.

Inspection is the last variable. Round features are easy to check with a micrometer or CMM. Wrapped surfaces and helical forms usually need a CMM program or a dedicated gauge. Ask for the inspection report before the parts ship if the feature is functional.

The clearest fit is a part with features on more than one face plus a round or near-round body. A hydraulic manifold with ports on four sides, a motor shaft with a keyway and cross-drilled holes, a sensor housing with a threaded bore and side windows. These parts need three or four setups on a three-axis mill. One four-axis setup covers them.

Cylindrical work with angular features is the second group. Cams, worms, splines, helical grooves and index rings. The A-axis indexes to each angular position, or feeds continuously for the helix. On a three-axis machine a cam profile usually means a rotary table used as a manual indexer, which is slower and depends on the operator.

Third is any part where concentricity between features matters. Turning a diameter and milling flats on the same centerline in one setup removes the stack-up you get from re-chucking. That single benefit often decides the process, even when the geometry itself looks simple.

The fourth group is medium-volume repeat work. Fixture once, run 50 or 500 parts, and the setup cost spreads out. Four-axis pays back on batch sizes that are too small for a dedicated fixture but too large to keep re-clamping by hand.

Parts that are basically a plate with holes on one face are not four-axis work. Neither are thin, flexible parts that deflect when the table rotates. Those stay on a three-axis machine or a mill-turn center.

The tool axis never tilts on a four-axis machine. Any feature that needs the cutter to reach behind a shoulder, cut a steep compound angle, or machine a deep pocket floor from an angle is out of reach. Those jobs go to a five-axis center, and we run 16 of them for exactly this reason.

Setup is another limit. A four-axis machine needs a chuck, a tombstone, or a custom fixture, and that fixture has to be dialed in. For a one-off prototype the dial-in time can exceed the cutting time. If the part is small and flat, a three-axis machine with a soft jaw is faster and cheaper.

Rigidity changes with part length. A long shaft supported only at the chuck behaves like a cantilever. Turning the table does not fix chatter, and sometimes makes it worse because the rotating mass is off center. Steady rests help, but they add setup and limit travel.

Programming is a smaller issue than most people expect. CAM software handles four-axis indexing and simultaneous paths well. The real cost is proving the program the first time, especially for wrapped surfaces where a small post-processor error shows up as a visible seam.

Cost is the honest answer for a lot of parts. If a three-axis machine can reach every feature in two setups and the tolerance is open, adding a rotary axis buys nothing. We quote both routes when the geometry is borderline.

Start with the fixture, not the program. Dial the chuck or tombstone to run out under 0.01 mm at the working radius, then indicate the part after clamping. If the part moves when the table rotates, the job is lost no matter how good the toolpath is.

Cut a test feature before the full run. One diameter and one indexed face tell you whether the rotary zero is where the CAM post says it is. This takes ten minutes and saves a scrapped batch. We do this on every new four-axis job.

Keep the part as close to the table center as the geometry allows. Off-center mass increases inertia and can introduce vibration at higher rotary speeds. Balance matters more on long parts and on heavy stainless or titanium blanks.

Inspect the first article, then spot-check through the run. Raw material check, in-process monitoring and final inspection cover the sequence, and we inspect 100% before shipment. Reports come on request.

Once the process is proven, four-axis work runs at the same pace as any other cell. Production can start within 24 hours of a released drawing, and parts ship in 3–5 days for typical jobs. Historical late-delivery probability sits below 2%.