What Can You Do With a Wood CNC Machine?
This page explains what a wood CNC router actually cuts, how its toolpaths differ from metal work, and where the process stops being economical. It is written for engineers and buyers who need to judge whether a wood part belongs on a router or on a mill.
How a wood CNC machine removes material
A wood CNC machine is a gantry or moving-table router that follows a CAM toolpath with a spinning cutter. The spindle sits on 2 or 3 linear axes, and the bed may add a 4th rotary axis for carved columns or curved chair parts. Cutting happens at the spindle nose, not at a tool turret, so the geometry you can reach depends on how far the gantry can travel and how deep the cutter can reach without rubbing the shank.
Wood is cut at high spindle speed and high feed. A 6 mm two-flute compression bit in 18 mm birch plywood typically runs 16,000–18,000 rpm at 4–6 m/min, taking 6–9 mm depth per pass. Chipload per tooth lands near 0.15–0.25 mm, which keeps the edge cutting instead of rubbing. Rub and the tool dulls in an hour. Cut cleanly and it lasts a full shift.
The trade-off is stiffness. Wood routers are built light so the gantry can accelerate fast across a 2,440 × 1,220 mm sheet. Push a 12 mm cutter through hard maple at a heavy chipload and the gantry flexes, the wall tapers, and the bottom edge tears out. Feed and speed tables for wood assume a light machine, so the numbers that work on a metal mill will chatter here.
Dust is the other half of the process. A 100 mm dust shoe on the spindle and 3,000 m³/h extraction keep chips out of the cut. Skip it and the cutter recuts the same chips until the edge dulls, the surface burns, and the finishing pass leaves a fuzzy wall.
Sheet nesting: cutting flat panels at volume
The most common job on a wood CNC router is nesting flat sheet. A CAM nest packs parts onto a 2,440 × 1,220 mm board in the order the cutter can reach them, then cuts the outlines with a compression bit so both faces stay clean. Cabinet sides, drawer boxes, shelves, and jigs all fall into this group.
The compression bit matters more than the machine. Its up-cut flutes at the tip and down-cut flutes above meet at a point that sits in the middle of the panel thickness. Set the cutter so that meeting point lands at half the board depth and both faces come out without tear-out. Set it wrong and the top face fuzzes while the bottom chips.
Nesting efficiency drives cost. A good nest reaches 75–85% material use on rectangular parts and drops to 60–70% once you add curved profiles. If your part is 300 × 200 mm and the sheet is 2,440 × 1,220 mm, the scrap rate is a real line item, not a rounding error. Design parts that tile and you cut both material and cycle time.
Hold-down is the failure point people underestimate. A vacuum table needs the panel to seal flat against the grid. Warped plywood or a cut that releases internal stress mid-job will lift, the cutter grabs, and the part cracks. Skim both faces first if the sheet has been stored on edge.
Joinery, pockets, and repeatable fits
Routers hold two dimensions tightly and one loosely. X and Y positions repeat well, often within 0.1 mm over a full sheet, because the gantry is a rigid frame and the ball screw or rack is ground. Z depth depends on how flat the bed is and how much the panel moves, so a 6 mm deep pocket may vary 0.1–0.3 mm across a 2,440 mm sheet.
That split shapes what joinery works. Through mortise and tenon, finger joints, dovetails, and pocket-screw counterbores all rely on X and Y, so they repeat cleanly job to job. Blind dados and hinge cups depend on Z, so they need a skimmed spoilboard and consistent panel thickness. Measure a stack of ten panels and you may find 18.0 to 18.4 mm, which is enough to sink a flush hinge cup.
Tool diameter sets the smallest inside corner. A 6 mm cutter leaves a 3 mm radius in every internal corner, so a square pocket needs a smaller tool or a dogbone relief. Designers who draw sharp internal corners in CAD hand the shop a problem that only a second operation or a corner-chisel tool can fix.
For repeated furniture runs, the win is not speed. It is that part 1 and part 400 come off the same program with the same fit. Hand-cut joinery drifts; a router does not. That consistency is what makes flat-pack assembly work on a line.
Relief carving and 3D contour work
Relief carving turns a 2D image into a height map and cuts it with a ball nose cutter in a raster pass. A 6 mm ball nose at 8–10% stepover, so roughly 0.5 mm between passes, gives a smooth surface on a 300 mm wide panel. Tighten the stepover to 0.2 mm and the surface improves, but the cycle time roughly triples.
Roughing and finishing are separate operations. A 6 mm flat end mill clears the bulk at 3–4 mm depth per pass and leaves a stepped surface. The ball nose then removes 0.3–0.5 mm of stock on the finish pass. Skip the roughing step and the ball nose takes the full depth, which snaps small tools and burns the surface.
3D contour work on a 4-axis rotary is where wood routers earn their keep for columns, chair legs, and turned profiles that are not round. A Ø400 mm rotary table with a tailstock handles parts up to about 2,000 mm long. Beyond that, the part whips unless you add a steady.
Carving is slow and that is the honest limit. A detailed 600 × 400 mm panel can run 4–8 hours of spindle time. If the same geometry can be molded, cast, or cut on a 5-axis mill from a pattern, the router is the wrong tool. Carving wins on one-offs, on solid wood where grain must show, and on parts too large to mold.
Where a wood CNC machine stops being the right choice
Tolerance is the first boundary. A router holds ±0.1 mm on well-fixtured flat parts and looser on tall or thin ones. Our metal machining centers hold ±0.005 mm, so if the drawing calls for a bearing bore, a press fit, or a sealing face, the part belongs on a mill, not a router. Wood also moves with humidity, so a 300 mm oak part can grow or shrink 0.5 mm between seasons no matter how well you cut it.
Hard materials change the math. MDF and plywood cut fast and hold shape. Solid hard maple, dense tropical species, and engineered stone-loaded composites dull carbide quickly and need slower feeds, which cuts the router speed advantage. Aluminum on a wood router is possible with a single-flute cutter at 18,000 rpm, but chip evacuation and rigidity are marginal. It is a prototype trick, not a production plan.
Geometry decides the rest. Deep narrow pockets, sharp internal corners, threads, and bores all fight the tool shape. Undercuts cannot be reached from above. If the part needs material added rather than removed, wood CNC is the wrong starting point.
Cost crosses over fast. One prototype panel on a router is cheap. Ten thousand identical small brackets are cheaper molded or die cut. The router wins in the band between roughly one and a few thousand parts, especially when the design is still changing and the toolpath is just a file edit.
Five wood CNC job types and what each one needs
Feed ranges assume a light gantry router with a 6 mm cutter in 18 mm sheet goods.
| Job type | Typical cutter | What decides success | Watch for |
|---|---|---|---|
| Sheet nesting | 6 mm compression bit | Nest efficiency and vacuum hold | Warped panels lifting mid-cut |
| Joinery and pockets | 6 mm up-cut or straight | Flat spoilboard, consistent thickness | Corner radii too small for the tool |
| Relief carving | 6 mm ball nose, 8–10% stepover | Stepover vs cycle time | Missing roughing pass |
| 4-axis contour | Ball nose or profile bit | Rotary alignment and tailstock | Long parts whipping |
| Prototype aluminum | Single-flute carbide | Chip evacuation, light depth | Tool welding to the work |
The short answer
If your part is flat, under ±0.1 mm, and made of sheet goods or solid wood, a wood CNC router is the fast and cheap route. If it needs a press fit, a bore, a thread, or ±0.005 mm, send it to a metal machining center instead.
Common questions
Can a wood CNC machine cut aluminum?
Yes, with a single-flute carbide cutter at high rpm and light depth per pass. The limits are chip evacuation and rigidity. Small flat plates and prototype brackets work. Deep pockets, tight tolerances, and long production runs do not.
How tight a tolerance can a wood router hold?
About ±0.1 mm on flat parts held on a vacuum table or fixture, and closer on X and Y than on Z. Wood itself moves with humidity, so a tight drawing tolerance on a wood part is often meaningless. Metal parts on our machining centers hold ±0.005 mm.
What file format does a wood CNC machine need?
STEP, IGES, or DXF for the geometry, and the CAM post produces the G-code. For 2D nesting a clean DXF with closed outlines saves setup time. For carving, a grayscale height map or a 3D mesh feeds the toolpath.
Why does my part have fuzzy edges?
Usually a dull cutter, the wrong bit for the face, or a compression bit set at the wrong depth. Chips left in the cut also burn and fuzz the surface. Check the dust shoe and the extraction before you change the toolpath.
When is a wood router cheaper than a 5-axis mill?
When the part is flat, large, and made of wood or plastic. Routers cut 2,440 × 1,220 mm sheets in one setup. A 5-axis mill is the better choice when the part needs metal, tight tolerance, and features that must be reached from several sides.
Send us your wood or metal part
Upload a STEP or DXF and we reply with a quote and DFM notes within 12 hours. Prototype to 10,000+ parts, no minimum order.
12-hour quote100% inspectionNo MOQNDA on request
More from the shop floor
We publish setup notes, tooling trials and inspection data from the factory floor.
